2D Sketch Creating and Placement Settings
When creating a 2D Shape/Sketch in the scene, you will be given available placement options to define the location of the sketch plane.
For Innovative Parts, these placement options are used just for defining the sketch original location. You can use the TriBall positioning tool to modify this location after the sketch plane is created. This plane is not associated to any placement option and will not change based on modification to the placement locations.
For Structured Parts, options are available to fix the sketch plane to the placement references. This fully associates the sketch plane to the placement location and modifications to the placement locations will update the sketch placement. This is useful to build design intent into the sketch placement to update based on changes to the previous model history structure.
To Create A 2D Shape/Sketch
- Select the 2D Shape Command on the Sketch Fluent Ribbon Bar.
- Alternatively, Select the Create 2D Shape X/Y/Z Plane option. This will create a plane on the X, Y, or Z global plane or on Active Parts at the X, Y, or Z origin location.
- Use the Placement Settings to define the location of the sketch.
- Select Ok to finish the placement settings (or this will automatically complete if the option is set).
- Draw the desired 2D sketch geometry.
- Select Finish on the Sketch Fluent Ribbon Bar or on the Edit-Cross Section dialog in the Toolbar UI.
Options Within The 2D Sketch Placement Command Browser
Select Structured Part. Available when there are no active parts in the scene. Structured Parts allow 2D Shapes to be placed under the part history structure. Select this option to select an existing Structure Part in the scene if this part was not set as active before entering the 2D Shape command.
2D Sketch Placement Type. Available placement options to define the location of the 2D Shape/Sketch plane.
- Point. Select this option to reference a point on existing geometry or a point in space/scene.
- 3-Point. Select 3-points to define the sketch plane that will pass through these points.
- Parallel to Face at Point. Select a Face and a Point to define a sketch plane that will be parallel to the face at the specified point.
- Offset From Face. Select a face/datum plane and enter a offset distance to define a sketch plane offset from the selected face/datum plane.
- Angle to Face. Select a face/datum plane, an linear edge/datum axis, and enter the angle value to define a sketch plane that is angled from the selected face/datum plane.
- Tangent to Cylindrical Face Through Point. Select a cylindrical face and a point to define a sketch plane that passes through the point and will be tangent to the face.
- Parallel to Edge. Select a linear edge or datum axis to define a sketch plane that is parallel to the selection.
- Normal to Curve at Point. Select a linear edge or 3D Curve and a point on that curve (or datum point) to define a sketch plane that is normal to the curve at the selected point location.
- Normal to Face. Select an existing face or datum plane to align the sketch plane normal to the selection. Use the advance options to determine the location for the origin and x-direction.
- Plane/Face. Select an existing face or datum plane to align the sketch plane. Use the advance options to determine the location for the origin and x-direction.
Selected Geometry. This list box will show the selections made for the placement types. Right-click in this list box for additional options to delete/clear.
Advance Options. Advance options for the placement of the sketch plane.
- Origin Point. Select this list box and select a point or datum point to define the origin of the sketch plane. This will change the sketch planes location but will satisfy the placement conditions used.
- X-Direction. Select this list box and select a linear edge or datum axis to define the x-direction of the sketch plane. This will change the sketch planes orientation but will satisfy the placement conditions used (in some placement conditions, this option will not be able to change the orientation since it may not satisfy the placement condition).
- Reverse Z-Direction. Reverse the Z-Direction of the sketch plane based on the placement location. Note: The Y-direction of the sketch plane will change locations to satisfy this change.
- Reverse X-Direction. Reverse the X-Direction of the sketch plane based on the placement location. Note: The Z and Y-direction of the sketch plane may change locations to satisfy this change..
- Fix to Reference. Available for Active Structured Parts Only, select this option to fix the placement locations and advance location options to the selections. Changes to the selections will update the location of the sketch plane.
- Finish Command if Conditions are Satisfied. Select this option to automatically complete the sketch plane placement once the conditions are satisfied base on the placement types.
- Automatically Determine Placement. Select this option to automatically determine the placement type based on the picking locations in the scene. When selected, the Radio Buttons for the placement types will not be selected by default and will be enabled when selections are made in the scene. Users can manually select the desired placement type radio button when this option is enabled. To keep the last pick placement type as the default for the next sketch plane creation, un-check this option.